Features and parameters
Turn sketches into solids, then drive them with parameters, sheet metal rules and plastic features.
The timeline is the model
Every feature is a step on the timeline, in the order it was created. The model you see is the result of replaying those steps. That has three consequences worth knowing from the start:
- Double-click a feature to edit it; the timeline rebuilds from there.
- Drag the marker back to see the design as it was at an earlier step.
- Reorder features by dragging them. A feature can only move above steps it does not depend on.
Solid features
| Feature | Key | What it does |
|---|---|---|
| Extrude | E | Pulls a closed profile along its normal. Distance, symmetric, through all, draft and thin-wall options. |
| Revolve | — | Turns a profile about an axis, with an angle and a direction. |
| Sweep | — | Moves a profile along a path, with twist and scaling options. |
| Loft | — | Blends between several profiles; use guide curves to control the shape. |
| Press Pull | Q | Offsets a face directly in the viewport, with or without a new sketch. |
| Hole | H | Simple, counterbore, countersink and tapped holes from presets. |
| Fillet / Chamfer | — | Rounds or bevels edges; constant or variable radius. |
| Shell | — | Hollows a body to a wall thickness, optionally removing faces. |
| Pattern | — | Linear or circular repeats of a feature, face or body. |
| Mirror | — | Mirrors features or bodies about a plane. |
| Combine / Split | — | Boolean union, subtract and intersect; split a body with a plane, face or another body. |
Surfaces use the same timeline. The Surface tab adds boundary surface, patch, trim, blend and match for continuous (G1/G2) transitions; surfaces can be knitted into a solid or used to cut one.
Parameters and expressions
User parameters are named values with units, created in Manage › Parameters. Any value box can use an expression instead of a number:
width / 2 - 61 in,30 deg— values with explicit unitshole_dia + 0.5 mm— mixed parameters and units
Change a parameter and every feature that uses it rebuilds. This is how a family of parts is driven from one design. Pressing the arrow keys in a value box steps a plain number by 1 (Shift by 10, Alt by 0.1) when Preferences › Design enables it.
Configurations store alternative sets of parameter values in the same file, so one design can produce several variants without copies. Use the configuration table to switch or compare them.
Sheet metal
Sheet metal parts are built from a rule: thickness, bend radius and K-factor. Set rules in Sheet Metal Rules, then:
- Flange — base flange from a closed profile, contour flange from an open sketch, or edge flange from a part edge. Edge flanges take height, angle, height-from and bend position.
- Hem — folds an edge back toward the sheet.
- Fold — bends along a sketch line.
- Unfold / Refold — work on the flat state and return.
- Convert — turns a constant-thickness plate into sheet metal.
- Create Flat Pattern — shows the flat part with bend lines and a bend table, and exports DXF or the bend-table CSV.
Bend reliefs are cut automatically where a flange ends at an inside corner, using the rule's relief width and depth. Flat lengths follow the rule's K-factor, so they match what a press brake will produce.
Plastic parts
MODEL › CREATE also holds the plastic features used in enclosures:
- Boss — screw bosses with a hole, root fillets and optional ribs.
- Lip / Groove — the mating lip and groove along a shell's opening.
- Snap Fit — a cantilever snap hook and its catch.
- Rest — a pad for the part to stand on.
Plastic Rules (Manage › Rules) set wall thickness, draft and clearance per material; the features use them as defaults. Rib and Web complete the set.
Order that avoids rework
- Fillet outside edges before shelling, so the shell follows the fillets. Edges of the face the shell removes are the exception: round them after the shell.
- For a fillet between two curved faces, shell first; the offset cannot always follow that fillet.
- Put holes and cuts after the main shape, and patterns after the feature they repeat.
- Keep the timeline short. If a step is only for one review, roll back instead of deleting it.